MeshedRegion#

class ansys.dpf.core.meshed_region.MeshedRegion(num_nodes=None, num_elements=None, mesh=None, server=None)#

Represents a mesh from DPF.

Parameters:

num_nodes (int, optional) – Number of nodes to reserve for mesh creation. The default is None.
num_elements (int, optional) – Number of elements to reserve for mesh creation. The default is None.
mesh (ansys.grpc.dpf.meshed_region_pb2.MeshedRegion) – The default is None.
server (ansys.dpf.core.server, optional) – Server with the channel connected to the remote or local instance. The default is None, in which case an attempt is made to use the global server.

Examples

Extract a meshed region from a model.

>>> import ansys.dpf.core as dpf
>>> from ansys.dpf.core import examples
>>> model = dpf.Model(examples.find_static_rst())
>>> meshed_region = model.metadata.meshed_region

Create a meshed region from scratch (line with 3 beam elements).

>>> import ansys.dpf.core as dpf
>>> meshed_region = dpf.MeshedRegion(num_nodes=4,num_elements=3)
>>> i=0
>>> for node in meshed_region.nodes.add_nodes(4):
...     node.id = i+1
...     node.coordinates = [float(i), float(i), 0.0]
...     i=i+1
>>> i=0
>>> for element in meshed_region.elements.add_elements(3):
...     element.id=i+1
...     element.connectivity = [i, i+1]
...     element.is_beam=True #or is_solid, is_beam, is_point
...     i=i+1
>>> meshed_region.elements.add_beam_element(id=4,connectivity=[3,0])

property elements#

All elemental properties of the mesh, such as connectivity and element types.

Returns:: elements – Elements belonging to the meshed region.
Return type:: Elements

Examples

>>> import ansys.dpf.core as dpf
>>> from ansys.dpf.core import examples
>>> model = dpf.Model(examples.find_static_rst())
>>> meshed_region = model.metadata.meshed_region
>>> elements = meshed_region.elements
>>> print(elements)
DPF Elements object with 8 elements

property faces#

All face properties of the mesh, such as faces_nodes_connectivity and face types.

Returns:: faces – Faces belonging to the meshed region.
Return type:: Faces

Examples

>>> import ansys.dpf.core as dpf
>>> from ansys.dpf.core import examples
>>> model = dpf.Model(examples.find_static_rst())
>>> meshed_region = model.metadata.meshed_region
>>> faces = meshed_region.faces
>>> print(faces)
DPF Faces object with 0 faces

property nodes#

All nodal properties of the mesh, such as node coordinates and nodal connectivity.

Returns:: nodes – Nodes belonging to the meshed region
Return type:: Nodes

Examples

>>> import ansys.dpf.core as dpf
>>> from ansys.dpf.core import examples
>>> model = dpf.Model(examples.find_static_rst())
>>> meshed_region = model.metadata.meshed_region
>>> nodes = meshed_region.nodes
>>> nodes.n_nodes
81

property unit#

Unit of the meshed region.

This unit is the same as the unit of the coordinates of the meshed region.

Returns:: unit
Return type:: str

property available_property_fields#

Returns a list of available property fields

Returns:: available_property_fields
Return type:: list str

property_field(property_name)#

Property field getter. It can be coordinates (field), element types (property field)…

Returns:: field_or_property_field
Return type:: core.Field or core.PropertyField

set_property_field(property_name, value)#

Property field setter. It can be coordinates (field), element types (property field)…

Parameters:

property_name (str) – property name of the field to set
value (PropertyField or Field) –

property available_named_selections#

List of available named selections.

Returns:: named_selections
Return type:: list str

named_selection(named_selection)#

Scoping containing the list of nodes or elements in the named selection.

Parameters:: named_selection (str) – Name of the named selection.
Returns:: named_selection
Return type:: Scoping

set_named_selection_scoping(named_selection_name, scoping)#

Named selection scoping setter.

Parameters:

named_selection_name (str) – named selection name
scoping (Scoping) –

deform_by(deform_by, scale_factor=1.0)#

Deforms the mesh according to a 3D vector field and an additional scale factor.

Parameters:

deform_by (Field, FieldsContainer, Result, Operator) – Used to deform the plotted mesh. Must output a unique 3D vector field. Defaults to None.
scale_factor (float, Field, FieldsContainer, optional) – Used to scale the mesh deformation. Defaults to 1.0. Can be a scalar Field (or a FieldsContainer with only one Field) to get a spatially non-homogeneous scaling.

property grid#

Unstructured grid in VTK format from PyVista.

Returns:: UnstructuredGrid of the mesh.
Return type:: pyvista.UnstructuredGrid

Examples

>>> import ansys.dpf.core as dpf
>>> from ansys.dpf.core import examples
>>> model = dpf.Model(examples.find_static_rst())
>>> meshed_region = model.metadata.meshed_region
>>> grid = meshed_region.grid

Plot this grid directly.

>>> grid.plot()

Extract the surface mesh of this grid

>>> mesh = grid.extract_surface()

plot(field_or_fields_container=None, shell_layers=None, deform_by=None, scale_factor=1.0, **kwargs)#

Plot the field or fields container on the mesh.

Parameters:

field_or_fields_container (dpf.core.Field or dpf.core.FieldsContainer) – Field or fields container to plot. The default is None.
shell_layers (core.shell_layers, optional) – Enum used to set the shell layers if the model to plot contains shell elements.
deform_by (Field, Result, Operator, optional) – Used to deform the plotted mesh. Must output a 3D vector field. Defaults to None.
scale_factor (float, optional) – Scaling factor to apply when warping the mesh. Defaults to 1.0.
**kwargs (optional) – Additional keyword arguments for the plotter. For additional keyword arguments, see help(pyvista.plot).

Examples

Plot the displacement field from an example file.

>>> import ansys.dpf.core as dpf
>>> from ansys.dpf.core import examples
>>> model = dpf.Model(examples.find_static_rst())
>>> disp = model.results.displacement()
>>> field = disp.outputs.fields_container()[0]
>>> model.metadata.meshed_region.plot(field)

deep_copy(server=None)#

Create a deep copy of the meshed region’s data on a given server.

This method is useful for passing data from one server instance to another.

Parameters:: server (ansys.dpf.core.server, optional) – Server with the channel connected to the remote or local instance. The default is None, in which case an attempt is made to use the global server.
Returns:: mesh_copy
Return type:: MeshedRegion

Examples

>>> import ansys.dpf.core as dpf
>>> from ansys.dpf.core import examples
>>> model = dpf.Model(examples.find_static_rst())
>>> meshed_region = model.metadata.meshed_region
>>> other_server = dpf.start_local_server(as_global=False)
>>> deep_copy = meshed_region.deep_copy(server=other_server)

field_of_properties(property_name)#

Returns the Field or PropertyField associated to a given property of the mesh

Parameters:: property_name (str, common.elemental_properties, common.nodal_properties) – Name of the property.
Returns:: properties
Return type:: Field, PropertyField

Examples

>>> import ansys.dpf.core as dpf
>>> from ansys.dpf.core import examples
>>> model = dpf.Model(examples.find_static_rst())
>>> meshed_region = model.metadata.meshed_region
>>> connectivity = meshed_region.field_of_properties(
...     dpf.common.elemental_properties.connectivity)
>>> coordinates = meshed_region.field_of_properties(dpf.common.nodal_properties.coordinates)